March 18, 2022 at 5:01 pmfriday.abolorunkeSubscriber
Description of my problem:
Immiscible gas-liquid multicomponent two-phase free surface flow. The gas and liquid phases are immiscible, while their components or species are miscible in both phases. I initially started with Eulerian model, but I want to switch to VOF method to get quick result for sanity check before running the full Euler model.
For my eulerian model, I have a UDF for species interphase mass transfer (define-linearized-mass-transfer) and interface momentum transfer during to the transfer of mass across the interface( define-exchange-property). Now, i see that I can't use the define exchange udf anymore in my VOF setup, bcos the option is not available on the phase interaction panel. And I must some how include my interface momentum balance in the set up.
March 18, 2022 at 8:00 pmDrAmineAnsys EmployeeYou need to restrict mass transfer to occur only in interfacial cells if you are using UDF. You can do everything Souce Macros but it's better to rely on dedicated mass transfer macros.
- Will Define_Source do the same job? If I reformulate my define-exchange property to define-source and add to the fluid zone as source term will that do same thing as my define-exchange-property udf.
- Do I have to include "if(grad_of_VolumeFraction ! = 0)" to my define-source udf to restrict the momentum change to the interface? or fluent will automatically do that for me?
March 18, 2022 at 8:17 pmfriday.abolorunkeSubscriberThank you for your response. Yes, I restricted my mass transfer to the interfacial cells using grad_vof !=0. I used the define linearized mass transfer macro.
I am asking if I should restrict the momentum source to the interfacial cells using same flag bcos the momentum transfer occurs at the interface or fluent will automatically know to do that.
More so, if i use define-source macro for my momentum source at the interface in the VOF model does it do same thing as define-exchange-property macro available in Eulerian model?
March 18, 2022 at 8:22 pmDrAmineAnsys EmployeeMdot will be zero elsewhere if done properly so you do not to restrict it again.
March 18, 2022 at 8:23 pmDrAmineAnsys EmployeeYou do not require momentum source for phase change with Vof model.
March 18, 2022 at 8:27 pmfriday.abolorunkeSubscriberThank you! This really helped a lot.
March 18, 2022 at 8:28 pmDrAmineAnsys EmployeeWelcome: why you do not need it -> in Vof both phases share same velocity so it is on bulk level zero if you want to add it .
March 18, 2022 at 9:51 pmfriday.abolorunkeSubscriberOh. Yes, your response made me think carefully about it and I realized it will be zero. Since the velocity of the liquid, gas and interface is the same that contribution to the momentum bal at the interface will be zero. See figure below for momentum bal at the interface (surface tension effect was neglected). The viscous normal stress term won't cancel out as the liquid and gas viscosities are different. However, the magnitude of this term (eqn in red) is small and won't really affect the physics that much.
To rigorously capture the physics of my problem I will be using the Eulerian model. In my problem, the liquid and gas velocities are different and pressure discontinuity is expected on the interface. For now, i just wanna use VOF to get a quick result and see if the model behaves as expected.
Viewing 7 reply threads
Ansys Innovation Space
- You must be logged in to reply to this topic.
Boost Ansys Fluent Simulations with AWS
Computational Fluid Dynamics (CFD) helps engineers design products in which the flow of fluid components is a significant challenge. These different use cases often require large complex models to solve on a traditional workstation. Click here to join this event to learn how to leverage Ansys Fluids on the cloud, thanks to Ansys Gateway powered by AWS.
Earth Rescue – An Ansys Online Series
The climate crisis is here. But so is the human ingenuity to fight it. Earth Rescue reveals what visionary companies are doing today to engineer radical new ideas in the fight against climate change. Click here to watch the first episode.
Subscribe to the Ansys Blog to get great new content about the power of simulation delivered right to your email on a weekly basis. With content from Ansys experts, partners and customers you will learn about product development advances, thought leadership and trends and tips to better use Ansys tools. Sign up here.Trending discussions
- Suppress Fluent to open with GUI while performing in journal file
- Floating point exception in Fluent
- What are the differences between CFX and Fluent?
- Heat transfer coefficient
- Getting graph and tabular data from result in workbench mechanical
- The solver failed with a non-zero exit code of : 2
- Difference between K-epsilon and K-omega Turbulence Model
- Time Step Size and Courant Number
- Mesh Interfaces in ANSYS FLUENT
- error in cfd post
© 2023 Copyright ANSYS, Inc. All rights reserved.Ansys does not support the usage of unauthorized Ansys software. Please visit www.ansys.com to obtain an official distribution.