February 2, 2019 at 12:37 amjoepa_2017Subscriber
I saw a good explanation of the difference between conformal and non-conformal meshes in another post. I can see that a conformal mesh is likely preferred when two surfaces are contacting each other.
If I have done simulations using non-conformal meshes but have used the mesh convergence tool, would that make the accuracy of the solution approach that of a conformal mesh? Or would that be unfair to say since the mesh convergence tool converges only on the maximum or minimum value? (i.e. perhaps the convergence tool has nothing to do with the nodes where the surfaces meet and form a non-conformal mesh) Also, if it's relevant, I am using bonded connections where the surfaces contact each other.
February 2, 2019 at 12:56 ampeteroznewmanSubscriber
I don't make much use of the mesh convergence tool, so I will leave others to comment on its accuracy, but that won't create a conformal mesh where none existed at the beginning.
When I have two bodies of different materials that move together because they are bonded, I first choose shared topology, which creates a conformal mesh, and let the two bodies be connected to the same nodes shared on the common face. If I want to study the stress in the bonded interface, then I change to bonded contact where I have more options for that study. I say two bodies of different materials because if they are the same material, then I could unite them in CAD. As you know, sometimes you can get a better quality mesh by splitting a single body into multiple bodies that are easier to mesh and using shared topology to connect them.
February 2, 2019 at 9:07 amjoepa_2017Subscriber
It makes sense that the mesh convergence tool wouldn't create a conformal mesh. I was just wondering if that could compensate for inaccuracies that a non-conformal mesh would introduce.
Also, if a non-conformal mesh is able to generate a solution, is there an obvious reason why a conformal mesh would no longer converge? I guess right now, I'm able to get a solution with a non-conformal mesh, so I wonder if I can keep using a non-conformal mesh; or would it be imperative to implement a conformal mesh?
February 2, 2019 at 3:12 pmpeteroznewmanSubscriber
One way to review the results of a non-conformal mesh is to request a Directional Displacement scoped to the two parts. Zoom in on the surface that has the bonded contact. On the legend, grab the line that separates red from the color below and drag it down until red fills one of the parts with red and back off a little so there is a couple of colors leading up to the bonded surface. Now grab the line that separated blue from the color above and drag it up until blue fills one of the parts and back off a little so there is a couple of colors leading up to the bonded surface. You have just created a very sensitive colormap to see displacement discontinuities across the bonded interface.
If you had a conformal mesh, the displacements must be continuous across the interface because there is a shared node. If the bonded contact allows some relative motion, you will see a step in the displacement contour. You can use the colormap to quantify the size of the step.
Two reasons a conformal mesh might not converge when a non-conformal mesh did converge is if the element size was larger on the conformal mesh, or if the element quality was worse on the conformal mesh.
February 25, 2020 at 7:09 amcs437Subscriber
At the interfacial phase between 2 fluids, I use both mesh methods. Why do conformal mesh and non-conformal mesh give different results in the case of 2 different materials moving together? Their iterations changed and went down differently under the same condition.
February 25, 2020 at 2:56 pmRobForum Moderator
Did you set a non-comformal interface up at the boundary? Which multiphase model were you using?
July 25, 2020 at 3:49 amcs437Subscriber
I did conformal mesh as shared topology at the interface between water and air since it moved together. The model I used is VOF. In this case, I get a meshing match very well at the interface and see the clear shape of a vortex. Is that in the right direction?
October 7, 2020 at 12:14 pmmario83SubscriberHi Peter, nI am trying to create a conformal mesh on an imported assembly. For what I found out, shared topology works only with the models created in ansys spaceclaim.nIs there a way to create a conformal mesh betwwen two bodies of different material after import the assembly cad model?nRegards,nMarion
October 10, 2020 at 10:02 pmpeteroznewmanSubscribernThe only way to get Shared Topology is to use either SpaceClaim or DesignModeler. If you have one of those, they can open a many types of files, then you can create a Multibody part and Share Topology.nIf you don't want to do that or don't have those licenses, then you can imprint the larger face with the outline of the smaller face to get identical faces, then use Mesh Controls to get a congruent mesh on both faces, and finally use Mesh Merge. That ends up being equivalent to Shared Topology, but is more work.n
- The topic ‘Conformal vs Non-Conformal Mesh’ is closed to new replies.
Boost Ansys Fluent Simulations with AWS
Computational Fluid Dynamics (CFD) helps engineers design products in which the flow of fluid components is a significant challenge. These different use cases often require large complex models to solve on a traditional workstation. Click here to join this event to learn how to leverage Ansys Fluids on the cloud, thanks to Ansys Gateway powered by AWS.
Earth Rescue – An Ansys Online Series
The climate crisis is here. But so is the human ingenuity to fight it. Earth Rescue reveals what visionary companies are doing today to engineer radical new ideas in the fight against climate change. Click here to watch the first episode.
Subscribe to the Ansys Blog to get great new content about the power of simulation delivered right to your email on a weekly basis. With content from Ansys experts, partners and customers you will learn about product development advances, thought leadership and trends and tips to better use Ansys tools. Sign up here.
- Floating point exception
- How to indetify baffles in Fluent meshing
- How to delete elements on Ansys Workbench
- Meshing cylindrical bodies with holes
- Quality failure limits are exceeded on some solid bodies… in ansys meshing
- Problems in the meshing of my geometry
- Ansys Mechanical – Python Scripting – Access and input parameter
- Mesh Element Quality Display Style Not Showing
- Local mesh refinement with targeted edge lengths at specified areas
- Fluent Meshing Batch Mode – Problems workflow commands
© 2023 Copyright ANSYS, Inc. All rights reserved.