November 3, 2020 at 5:19 pmkailashSubscriberWhenever my residual spikes up, the k and epsilon spikes the most. Is there anything that I can do to prevent this spike?n
November 3, 2020 at 5:41 pmSurya DebAnsys EmployeeHello, nWhat is the application that you are solving? Also please check the region where you have excess TKE getting produced. Do you think you need mesh refinement in those regions? Check your wall Y+ values as well.nFurther more is this Standard k-epsilon with Standard wall functions? Did you also try the option Production Limiter?nIf you have very wide range of wall Y+ variations, then you could try and use Scalable Wall Functions as well as it makes sure to scale the mesh virtually in regions where the wall Y+ is low. This ensures that the logarithmic profile is maintained.nBut again this depends on the type of application, the mesh resolution, the boundary conditions specially in terms of the turbulence parameters.nRegards,nSuryan
November 3, 2020 at 5:54 pmkailashSubscriberHi. Yes I have wide variations in wall Y+. My application is studying how the mixing performance is when gas is injected into a large tank (about 100,000 gallons). I am not concerned about any drag or lift or flow separation, so I am using k-e model only with scalable wall function. nI haven't tried Production limiter, what is that? can you please tell more about it?nThanks and Regards,nKailashn
November 3, 2020 at 6:37 pmkailashSubscriberI just got to know about the production limiter. I am getting a default value of 10. Should i just leave it as such and run? What does it exactly does? does it limit the upper limit of the epsilon value when those spikes occurs?nRegards,nKailash R.n
November 3, 2020 at 7:51 pmSurya DebAnsys EmployeeHello, nYou have a couple of options like Production Limiter and Production Kato-Launder. RANS equations consider a very high degree of correlation of Reynolds Stress Tensor with Strain Rate Tensor. This is why near stagnation regions, where the velocity suddenly goes to zero, there can be very high strain rates and velocity gradients. So RANS models can predict very large K values in these regions whereas it should actually decrease the production of K near those regions due to velocity being very small.nThe Production limiter works on that and calibrates the local level of the production of K term. This is also based on the local levels of dissipation. 10 is the default value but you can change it as well.nProduction Kato-Launder on the other hand utilizes a production limiter term that employs vorticity rates as well. nDo you see these high values of K near the stagnation point where the jet impinges on the tank wall?nRegards,nSuryan
November 3, 2020 at 8:33 pmkailashSubscriberYou are perfectly right. I am getting high values at the stagnation point only. Thanks for explaining the reason behind it.nRegards,nKailash R.nn
- You must be logged in to reply to this topic.
Simulation World 2022
Check out more than 70 different sessions now available on demand. Get inspired as you hear from visionary companies, leading researchers and educators from around the globe on a variety of topics from life-saving improvements in healthcare, to bold new realities of space travel. Take a leap of certainty and check out a session today here.
Earth Rescue – An Ansys Online Series
The climate crisis is here. But so is the human ingenuity to fight it. Earth Rescue reveals what visionary companies are doing today to engineer radical new ideas in the fight against climate change. Click here to watch the first episode.
Subscribe to the Ansys Blog to get great new content about the power of simulation delivered right to your email on a weekly basis. With content from Ansys experts, partners and customers you will learn about product development advances, thought leadership and trends and tips to better use Ansys tools. Sign up here.
- Suppress Fluent to open with GUI while performing in journal file
- Heat transfer coefficient
- What are the differences between CFX and Fluent?
- Floating point exception in Fluent
- The solver failed with a non-zero exit code of : 2
- Getting graph and tabular data from result in workbench mechanical
- Difference between K-epsilon and K-omega Turbulence Model
- Time Step Size and Courant Number
- Mesh Interfaces in ANSYS FLUENT
- error in cfd post
© 2022 Copyright ANSYS, Inc. All rights reserved.