February 27, 2023 at 5:21 pmjavat33489Subscriber
Hello. I want to simulate the movement of one part under the force of gravity down, but it flies away and does not see the contact in the other. Flat task. In contact, I tried everything, set the radius, changed the type of contact. The part as if does not see the contact and flies through.
What could be the problem? Thank you.
February 28, 2023 at 2:25 pmRahul KumbharAnsys Employee
Under the connection, insert the contact tool and check its initial status. This contact status should be close.
February 28, 2023 at 3:35 pmDave LoomanAnsys Employee
Maybe do an initial step where you hold the bodies in place to establish the initial contact.
February 28, 2023 at 4:09 pmmjmiddleAnsys Employee
The time step needs to be small enough so that contacts are within the pinball radius during a substep. Otherwise it can go from far outside contact pinball above to far outside pinball below in one time step and is never within the pinball radius to detect contact. You can increase the contact pinball, but usually you need to make time stepping low enough. There is a contact setting "predict for impact" to help with this, and you can set time stepping in the analysis settings. Also, be aware that transient usually needs some damping, either global or local. If contacts impact, they can rebound with even more energy due to the contact stiffness behavior and then the next near-contact detection can be moving faster and fly through. This behavior is noticable when viewing the time history. Lowering contact stiffness can recduce that behavior but the analysis really needs damping to prevent it.
March 1, 2023 at 1:02 ampeteroznewmanSubscriber
If the part is in free fall, meaning that the only force acting on the part is gravity, the correct way to model this is to calculate the impact velocity from the distance of the fall, and assemble the parts so that the falling part is positioned at the point of contact. The falling part is given the Initial Condition of a downward velocity equal to the impact velocity. That means that at time=0, the contact is already closed and ready to begin decelerating the part.
Calculating the impact velocity from the drop height is a simple physics equation, or you can use an online calculator.
You still have to turn on Auto Time Stepping and make the Initial Time Step a small number like 1e-4 s, the Minimum Time Step 1e-6 s and the Maximum Time Step 1e-3 s.
- You must be logged in to reply to this topic.
Boost Ansys Fluent Simulations with AWS
Computational Fluid Dynamics (CFD) helps engineers design products in which the flow of fluid components is a significant challenge. These different use cases often require large complex models to solve on a traditional workstation. Click here to join this event to learn how to leverage Ansys Fluids on the cloud, thanks to Ansys Gateway powered by AWS.
Earth Rescue – An Ansys Online Series
The climate crisis is here. But so is the human ingenuity to fight it. Earth Rescue reveals what visionary companies are doing today to engineer radical new ideas in the fight against climate change. Click here to watch the first episode.
Subscribe to the Ansys Blog to get great new content about the power of simulation delivered right to your email on a weekly basis. With content from Ansys experts, partners and customers you will learn about product development advances, thought leadership and trends and tips to better use Ansys tools. Sign up here.
- Saving & sharing of Working project files in .wbpz format
- Solver Pivot Warning in Beam Element Model
- Understanding Force Convergence Solution Output
- An Unknown error occurred during solution. Check the Solver Output…..
- What is the difference between bonded contact region and fixed joint
- whether have the difference between using contact and target bodies
- The solver engine was unable to converge on a solution for the nonlinear problem as constrained.
- User manual
- Colors and Mesh Display
- material damping and modal analysis
© 2023 Copyright ANSYS, Inc. All rights reserved.