October 6, 2020 at 5:17 pmtwataSubscriberWhat does the following warning mean?One or more MPC contact regions or remote boundary conditions may have conflicts with other applied boundary conditions or other contact or symmetry regions. This may reduce solution accuracy.nDo I have to worry about this warning message?
October 7, 2020 at 3:47 pmHuiLiuAnsys EmployeeThis can happen when some of the same geometry scopings are selected for MPC contacts or for any remote constraints, such as joints, remote force/displacement, point mass, remote points. Rigid bodies can also trigger the warning with the way Ansys internally connects them to the point mass at the centroid. This warning may not mean anything to the solution, or it may mean one of each pair of conflicting boundary conditions gets deactivated. So one should at least understand what is causing it. Go to Solution information and switch to the Graphics tab to see the red connection lines. Check for multiple connections to the same geometry entities. For contacts, one can right click on the Connections branch and choose. Check Overlapping Contact Regions. Here is a typical warning in the Solution Information if a constraint was deactivated, which is the worst case scenario: *WARNING*: No MPC equations were built for the contact pair identified by real constant set 5 due to overconstraint detection logic. Please check your model carefully. Click on the Solution Information. Press ctrl-F to search. Search for unique text in this warning that doesn't include specific model information like a real constant set number, such as overconstraint detection logic or No MPC equations. If no constraints were deactivated, then one can probably ignore the warningn
- You must be logged in to reply to this topic.
Simulation World 2022
Check out more than 70 different sessions now available on demand. Get inspired as you hear from visionary companies, leading researchers and educators from around the globe on a variety of topics from life-saving improvements in healthcare, to bold new realities of space travel. Take a leap of certainty and check out a session today here.
Earth Rescue – An Ansys Online Series
The climate crisis is here. But so is the human ingenuity to fight it. Earth Rescue reveals what visionary companies are doing today to engineer radical new ideas in the fight against climate change. Click here to watch the first episode.
Subscribe to the Ansys Blog to get great new content about the power of simulation delivered right to your email on a weekly basis. With content from Ansys experts, partners and customers you will learn about product development advances, thought leadership and trends and tips to better use Ansys tools. Sign up here.
- How to calculate the residual stress on a coating by Vickers indentation?
- An Unknown error occurred during solution. Check the Solver Output…..
- Saving & sharing of Working project files in .wbpz format
- Solver Pivot Warning in Beam Element Model
- Understanding Force Convergence Solution Output
- Colors and Mesh Display
- whether have the difference between using contact and target bodies
- The solver engine was unable to converge on a solution for the nonlinear problem as constrained.
- Massive amount of memory (RAM) required for solve
- What is the difference between bonded contact region and fixed joint
© 2022 Copyright ANSYS, Inc. All rights reserved.