March 18, 2021 at 3:15 pmashansysSubscriberFor example in the beam model, one can specify the following boundary condition at both the ends of a slender circular bar:nUx = Uy = Uz = 0 ;nRx = Ry = Rz = free nIf a solid model is used instead of a beam model, applying Ux = Uy = Uz = 0 at the end faces would also arrest rotational degrees of freedom on those faces and it would act as a fixed boundary condition. nSo how can a simply supported condition be applied in the solid model?n
March 18, 2021 at 4:31 pmpeteroznewmanSubscribernSelect the end face of the solid and select Remote Displacement from the Support category. You can fix three translations and leave the three rotations Free. Repeat on the other end except you cannot leave three rotations free at both ends. One end must have rotation about the axis along the beam length set to zero, otherwise the solver would see a zero pivot error. This is true for a beam model and a solid model with Remote Displacements.n
March 18, 2021 at 4:42 pmashansysSubscriberThanks for the answer. I am aware of the option of applying remote displacements on remote points created with surfaces, however, I am looking for answers based on the physics of formulations of 1D and 3D elements. n
March 18, 2021 at 4:47 pmpeteroznewmanSubscribernThe answer I gave is how to create a pinned connection on 3D solid elements meshed on a solid body. This gives the same boundary conditions as a 1D beam. I can only add that you should set the Behavior of the Remote Displacement as Rigid to fully match the 1D beam condition. What information is missing?nAre you asking how to do that if you just have nodes and elements and no solid body?n
March 18, 2021 at 5:00 pmashansysSubscribernIn a way, yes!nSo I want to know whether the answer can be derived from the very basics, i.e. based on various elemental formulations? For example for Euler Bernoulli beam theory or Timoshenko beam theory for beam models vs solid models.n
March 18, 2021 at 7:15 pmpeteroznewmanSubscribernANSYS BEAM188 implements Timoshenko beam theory, which includes Shear Deformation, so will have the closest agreement with a solid model.nANSYS BEAM4 implements Euler-Bernoulli beam theory, which ignores Shear Deformation, so will differ from a solid model, especially for short beam lengths.nSolid elements will need about 4 quadratic elements or 8 linear elements through the thickness of the beam to accurately capture the bending stress.n
- You must be logged in to reply to this topic.
Earth Rescue – An Ansys Online Series
The climate crisis is here. But so is the human ingenuity to fight it. Earth Rescue reveals what visionary companies are doing today to engineer radical new ideas in the fight against climate change. Click here to watch the first episode.
Subscribe to the Ansys Blog to get great new content about the power of simulation delivered right to your email on a weekly basis. With content from Ansys experts, partners and customers you will learn about product development advances, thought leadership and trends and tips to better use Ansys tools. Sign up here.
- Saving & sharing of Working project files in .wbpz format
- An Unknown error occurred during solution. Check the Solver Output…..
- Understanding Force Convergence Solution Output
- Solver Pivot Warning in Beam Element Model
- Colors and Mesh Display
- How to calculate the residual stress on a coating by Vickers indentation?
- whether have the difference between using contact and target bodies
- What is the difference between bonded contact region and fixed joint
- The solver engine was unable to converge on a solution for the nonlinear problem as constrained.
- User manual
© 2023 Copyright ANSYS, Inc. All rights reserved.