September 27, 2017 at 11:19 amadminAnsys Employee
How do I obtain a smooth restart for small mesh changes?
October 17, 2017 at 6:02 amadminAnsys Employee
There are 2 ways for performing a restart in a case with only a slightly modified mesh: 1. The standard approach is to use the interpolator a) If the meshes have a different mesh topology, then this is the only alternative. The restart will not be smooth, e.g. residuals show a jump, as the solution fields have to be interpolated on the new mesh. b) If the mesh topology is identical for mesh1 and mesh2, i.e. only changes in vertex co-ordinates, then the solution fields can just be copied onto the new mesh file. This is done by the interpolator when setting the following environment variable. CFXINTERPNOCRDVXCHECK = 1 The restart will be smoother than case a), but will still show some jumps in residuals, as boundary IP flows (such as wall shear and wall heat flux) and as hybrid values, are not interpolated onto the new mesh. 2. If the mesh topology is identical, the def-file of the new mesh can just be appended to the result-file of mesh1 by the following command: cat mesh1.res mesh2.def > mesh2restart.def cfx5solve –def mesh2_restart.def The order of the files in the cat-command is important. Restarting with this method will be smooth, depending on the changes in the mesh co-ordinates.
- You must be logged in to reply to this topic.
Simulation World 2022
Check out more than 70 different sessions now available on demand. Get inspired as you hear from visionary companies, leading researchers and educators from around the globe on a variety of topics from life-saving improvements in healthcare, to bold new realities of space travel. Take a leap of certainty and check out a session today here.
Earth Rescue – An Ansys Online Series
The climate crisis is here. But so is the human ingenuity to fight it. Earth Rescue reveals what visionary companies are doing today to engineer radical new ideas in the fight against climate change. Click here to watch the first episode.
Subscribe to the Ansys Blog to get great new content about the power of simulation delivered right to your email on a weekly basis. With content from Ansys experts, partners and customers you will learn about product development advances, thought leadership and trends and tips to better use Ansys tools. Sign up here.
- Conformal vs Non-Conformal Mesh
- ANSYS Workbench Measuring within Design
- Error in meshing
- The mesh file exporter could not resolve cyclic dependencies in overlapping contact regions error
- Meshing Error
- Ansys 19.0 – will not create mesh
- Can I view which mesh files (the names of them) are loaded into Fluent?
- Dealing with inflation layers around sharp corners in Ansys workbench meshing
- Mathematical model stuck at 1% with a warning of remote displacement
- how to improve the inflation quality at sharp corners?