December 6, 2018 at 7:35 pmxiaofuliSubscriber
I import a 3D geometry file from solidworks into ANSYS Workbench 18.1, I tried to make a conformal quad mesh within the whole structure, but it does not work, I use the split body function in the Spaceclaim to make the model into 3 different parts and use the mesh method with hex dominant. I even increase the number of the elements, it does not work very well, defeaturing mesh and triangle elements still occur. Could someone give me some help?
December 6, 2018 at 7:53 pmSandeep MedikondaAnsys Employee
December 6, 2018 at 8:44 pmxiaofuliSubscriber
Thanks for the help
I tried with sweep method, but the error will happen in this case and the face meshing does not work as well. Additionally, I could not log in to open the link you sent it to me. I hope that you could give me some detailed information about my question.
December 6, 2018 at 8:56 pmSandeep MedikondaAnsys Employee
If you don't know how to use online help, please see here.
December 6, 2018 at 9:07 pm
December 7, 2018 at 7:38 pmSandeep MedikondaAnsys Employee
Li, meshing often receives a lot of improvements in a version change. So, I recommend you to upgrade the latest version (19.2). Which you can easily download from the first figure at the top of this page.
Also, help has moved online only in v19 or later, looks like you have the older help viewer. In this, case you might want to search for Mesh Sweeping in the Meshing Users Guide.
December 8, 2018 at 3:52 ampeteroznewmanSubscriber
I'm travelling and this laptop only has 18.2 so I can't give you back an 18.1 archive, but I will make screen shots to explain.
1) The geometry has overlapping solids causing interference. Fix that in SpaceClaim by using the flat face of the long part to Split Body on the end part to delete the triangular piece. I will assume you did that. Next, in SpaceClaim, set Share Topology to Share.
Sandeep thinks as I do, that Sweep is a good Method in this case. In Mechanical, RMB on Mesh and Show Sweepable Bodies. The long part will not turn green. The reason is the faces don't match on the top and bottom. At most of the junctions, there is a line across the top and bottom face at the transition. At one of the junctions, there is no line. There either has to be all lines or no lines in order to sweep. Do you see the missing line?
Unless you need to divide the face to apply a load, it is best to remove all unnecessary lines. This is easily done in SpaceClaim by picking the Repair tab and then clicking the Extra Edges button. It will remove all the lines on the top and bottom face. Refresh the Project then in Mechanical, RMB on Mesh and Show Sweepable Bodies and the long part turns green.
2) You mentioned you are losing features due to mesh defeaturing, so turn it off.
3) Delete all the Hex Dominant mesh controls and add a Mesh Control Method called Sweep.
I see now why you had those lines!
To Sandeep's point about improvements to meshing in each version, here is what the 19.2 mesh looked like with the edges removed.
When I added the missing line, the body didn't show as Sweepable. Instead, I Split Body at each transition. Now with Sweep Method applied to just the center body, all the other bodies follow along because of the Shared Topology.
December 8, 2018 at 8:22 pmxiaofuliSubscriber
Thanks very much for your helpful reply.
1. I followed your instructions, delete the overlapped parts and also make the whole body sweepable, but there is one issue that I could not solve, There is no option that I could choose share for share topology. As it shown below.
2. After I follow all the steps, the shorter part (in green color) has distorted quad element mesh, as for this issue, how could I make the whole body has a very uniform quad mesh, the workbench file is attached, if you open up the transient structural analysis with the name "mesh_improvement", you will see this mesh problem.
Thanks for the help
December 9, 2018 at 2:54 pmpeteroznewmanSubscriber
1. You have to pick the system at the top of the tree in the outline then in the window below you can find Share Topology.
2. I assume the most important elements are around the hole. When you sweep a single body, select a Source face in the sweep, then RMB on the sweep and Inflate this Method. You then get an inflation mesh control with the face already selected. Use the Edge filter to select the edge of the hole. Also add a sizing control to this edge and specify 18 divisions.
December 9, 2018 at 6:49 pmxiaofuliSubscriber
Thanks very much for the helpful reply
1. I am using the 18.1 of Workbench, but there is no share option within share topology, I do pick the whole geometry, as you could see the SYS2 in orange color shown below, is it the reason that I do not have it in my ANSYS package? I tried with the merge option. but it does not work for the conformal mesh.
2. I follow your instructions concerning "select a Source face in the sweep, then RMB on the sweep and Inflate this Method. You then get an inflation mesh control with the face already selected. Use the Edge filter to select the edge of the hole. Also add a sizing control to this edge and specify 18 divisions", but the issue is that I waited around 1 hour, the mesh still does not finish, could you please open up the transient structural analysis with the name "mesh_improvement" to check whether there is some thing wrong with my manipulation?
Thanks very much
December 10, 2018 at 3:18 ampeteroznewmanSubscriber
1. I only have 18.2 with me today. In 18.1 try to use the Workbench tab and click on the Share button.
2. A few things were wrong with your attempt.
a. The Mesh settings had sizes that were too large for the geometry. Here is what worked.
b. You defined a Sweep with a Source Face, which was good...
...but you picked the opposite side of the part to define Inflation, it should be the same side as the Source face.
You need these settings for Inflation.
You also picked the opposite side for the edge sizing, it should be the same side as the Source face.
With those settings you get this mesh on one end...
...and you get this mesh on the other.
Here are the Mesh Metrics for Skewness.
December 13, 2018 at 8:33 pmxiaofuliSubscriber
Thanks for the helpful reply
The mesh generation part works very well as I followed your instructions, but the share option button is in grey color and I could not pick it manually, is it the reason that I might not have it in my ANSYS package, in this case, will it influence the mesh quality for conformal mesh?
December 13, 2018 at 8:53 pmSandeep MedikondaAnsys Employee
Click on SharePrep.
- You must be logged in to reply to this topic.
Simulation World 2022
Check out more than 70 different sessions now available on demand. Get inspired as you hear from visionary companies, leading researchers and educators from around the globe on a variety of topics from life-saving improvements in healthcare, to bold new realities of space travel. Take a leap of certainty and check out a session today here.
Earth Rescue – An Ansys Online Series
The climate crisis is here. But so is the human ingenuity to fight it. Earth Rescue reveals what visionary companies are doing today to engineer radical new ideas in the fight against climate change. Click here to watch the first episode.
Subscribe to the Ansys Blog to get great new content about the power of simulation delivered right to your email on a weekly basis. With content from Ansys experts, partners and customers you will learn about product development advances, thought leadership and trends and tips to better use Ansys tools. Sign up here.
- ANSYS Workbench Measuring within Design
- Conformal vs Non-Conformal Mesh
- Error in meshing
- Meshing Error
- The mesh file exporter could not resolve cyclic dependencies in overlapping contact regions error
- Ansys 19.0 – will not create mesh
- Dealing with inflation layers around sharp corners in Ansys workbench meshing
- Can I view which mesh files (the names of them) are loaded into Fluent?
- How to resolve Mesh Failure
- how to improve the inflation quality at sharp corners?