December 12, 2022 at 10:26 pmbenda83Subscriber
When I create a revolved geomatry (via SpaceClaim or other CAD software) and then try to mesh it in the structural analysis module - I find it quite challanging to create an HEX mesh.
Changing the mesh size, using the hex dominant or MultiZone methods - all feel like a voodoo. It may become successful sometimes, but sometime all I get is tetra mesh.
Is there a way to "tell" the software that there is a constant cross section that was revolved along a specific axis? Is there any other way that can improve the chances for a good hex mesh in this case?
December 13, 2022 at 12:43 ampeteroznewmanSubscriber
If the geometry is purely a revolved feature, and the loads are axisymmetric, then you should create an axisymmetric model and only mesh the surfaces on a radial slice in the X-Y plane where Y is the axis of revolution.
If you need to apply loads in 3D, then you can still bring in just the radial slice, but use the Pull feature to revolve the 2D mesh around the axis. Here is the 2D mesh:
Here is the 3D mesh after using the Pull feature.
December 13, 2022 at 10:04 amErik KostsonAnsys Employee
If it is really axisymmetric (about a global axis) then it could be possible to sweep mesh (Method), using the axisymmetric algorithm (choose this option in the Sweep Method definition and under Algorithm setting -> choose Axisymmetric )
All the best
December 13, 2022 at 10:22 amRahul KumbharAnsys Employee
If it is revolved geometry, you can slice in two 180 degree sections and use 'Sweep mesh method'
December 13, 2022 at 6:46 pmbenda83Subscriber
Thank you all guys.
What do I do in case this geomatery is a part of assembly. The mating parts or not revolved features and there should be specific connetions between them?
Or in a case the feature is almost purely revolved, but has several holes (for instance) that break this definition?
In these cases, starting from a surface and revolve the mesh, or slicing the geomatry may not be helpful. I think what Erik suggested is closest to what I imagined - should the revolve axis be located excectly on the global coordinate system?
December 13, 2022 at 7:30 pmpeteroznewmanSubscriber
If there are holes in the part that break the axisymmetry, then you can’t use these sweep methods without splitting the body up into sweepable pieces. It may help hex meshing to use a plane to split the body through the center of the hole.
- You must be logged in to reply to this topic.
Earth Rescue – An Ansys Online Series
The climate crisis is here. But so is the human ingenuity to fight it. Earth Rescue reveals what visionary companies are doing today to engineer radical new ideas in the fight against climate change. Click here to watch the first episode.
Subscribe to the Ansys Blog to get great new content about the power of simulation delivered right to your email on a weekly basis. With content from Ansys experts, partners and customers you will learn about product development advances, thought leadership and trends and tips to better use Ansys tools. Sign up here.
- Saving & sharing of Working project files in .wbpz format
- An Unknown error occurred during solution. Check the Solver Output…..
- Understanding Force Convergence Solution Output
- Solver Pivot Warning in Beam Element Model
- Colors and Mesh Display
- How to calculate the residual stress on a coating by Vickers indentation?
- whether have the difference between using contact and target bodies
- What is the difference between bonded contact region and fixed joint
- The solver engine was unable to converge on a solution for the nonlinear problem as constrained.
- User manual
© 2023 Copyright ANSYS, Inc. All rights reserved.